Materials can be set up to use specific tools instead of using the default tools. Tool overrides can be set up for both routing operations and border operations. A tool override can be set up by accessing the Library Specification Groups or Project Specification Groups and then editing a shared or project level material.

A tool override must be added to the code field. In the image above, a tool override has been added for both routing and border operations. The routing tool is listed first with the pipe symbol “|” preceding the border tool. Each tool (maximum of two), must be typed as “T<Common Tool Number>.”

A feed speed override is optional. If you include one, type it after the tool number as “F<feed speed>.” An override without a feed speed (example 4 below) is valid.

If only a border tool override is being used, the tool must be preceded by the pipe symbol “|”. If only a routing tool override is being used, it must be followed by the pipe symbol “|”.

Example: T<common tool #> F<feed speed>|T<common tool #> F<feed speed>

1. T101 F1000|T102 F2000 – routing and border tools, each with a feed speed

2. T101 F1000| – routing tool only

3. |T102 F2000 – border tool only, with a feed speed

4. |T102 – border tool only, no feed speed override

A tool number on its own (for example T8) is not a valid override. Write T8| for a routing tool or |T8 for a border tool.

A border (cut-out) tool override must always start with the pipe symbol, for example |T101. The first tool in the Code field is always read as the routing tool, so an entry such as T101 with no leading pipe is not applied to the border route.

If border routes are cutting with the wrong tool, or a material's parts are not cut free as expected, open the material, check its Code field, and confirm that the border tool is preceded by "|".

If you add a sheet to an existing nest and move parts onto it, the G-code for the nest has to be regenerated. On an auto-labeling machine you must use Create New G-Code from Drawing, not Update G-Code from Drawing. See Auto-Labeling and Creating New G-Code.

If the new sheet still uses a different border tool after creating new G-code, open a support case and include the work order and tool file.